pycatia.knowledge_interfaces.parameters¶

Module initially auto generated using V5Automation files from CATIA V5 R28 on 2020-06-11 12:40:47.360445

Warning

The notes denoted “CAA V5 Visual Basic Help” are to be used as reference only. They are there as a guide as to how the visual basic / catscript functions work and thus help debugging in pycatia.

class pycatia.knowledge_interfaces.parameters.Parameters(com_object)¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)

System.IUnknown

System.IDispatch

System.CATBaseUnknown

System.CATBaseDispatch

System.Collection

Parameters

Represents the Parameters collection of the part or the

product.

The following example shows how to retrieve it:

Dim CATDocs As Documents

Set CATDocs = CATIA.Documents

Dim part1 As Document

Set part1 = CATDocs.Add(“CATPart”)

Dim parameterList As Parameters

Set parameterList = part1.Part.Parameters

all_parameters()¶

Returns: list(Parameter())

create_boolean(i_name: str, i_value: bool) → pycatia.knowledge_interfaces.bool_param.BoolParam¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Func CreateBoolean(CATBSTR iName,

boolean iValue) As BoolParam

Creates a boolean parameter and adds it to the part’s collection of

parameters.

Parameters:

iName

The parameter name

iValue

The parameter value

Example:

This example creates the checked boolean parameter and adds it to the

newly created part:

Dim CATDocs As Documents

Set CATDocs = CATIA.Documents

Dim part1 As Document

Set part1 = CATDocs.Add(“CATPart”)

Dim chk As BooleanParam

Set chk = part1.Part.Parameters.CreateBoolean (“checked”, False)

Parameters

i_name (str) –
i_value (bool) –

Return type

BoolParam

create_dimension(i_name: str, i_magnitude: str, i_value: float) → pycatia.knowledge_interfaces.dimension.Dimension¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Func CreateDimension(CATBSTR iName,

CATBSTR iMagnitude,

double iValue) As Dimension

Creates a user dimension and adds it to the part’s collection of

parameters.

Parameters:

iName

The dimension name

iMagnitude

The dimension magnitude. Units are those of the IS system. Valid

magnitudes are:

“LENGTH”: the unit is the meter.

“ANGLE”: the unit is the radian.

The

Dimension object provides the Dimension.ValuateFromString method with

which you may express the value in any unit for a given dimension (see the

example below).

iValue

The dimension value provided as a real number

Example:

This example creates a LENGTH dimension and adds it to the newly

created part. The initial value is expressed in meters. The new value is

expressed in millimeters.

Dim depth As Dimension

Set depth = parameters.CreateDimension(“depth”, “LENGTH”, 20)

depth.ValuateFromString(“300mm”);

Parameters

i_name (str) –
i_magnitude (str) –
i_value (float) –

Return type

Dimension

create_integer(i_name: str, i_value: int) → pycatia.knowledge_interfaces.int_param.IntParam¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Func CreateInteger(CATBSTR iName,

long iValue) As IntParam

Creates an integer parameter and adds it to the part’s collection of

parameters.

Parameters:

iName

The parameter name

iValue

The parameter value

Example:

This example creates the RevisionNumber integer parameter and adds it

to the newly created part:

Dim CATDocs As Documents

Set CATDocs = CATIA.Documents

Dim part1 As Document

Set part1 = CATDocs.Add(“CATPart”)

Dim revision As IntParam

Set revision = part1.Part.Parameters.CreateInteger (“RevisionRumber”, 17)

Parameters

i_name (str) –
i_value (int) –

Return type

IntParam

create_list(i_name: str) → pycatia.knowledge_interfaces.list_parameter.ListParameter¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Func CreateList(CATBSTR iName) As ListParameter

Creates a list parameter and adds it to the part’s collection of

parameters.

Parameters:

iName

The parameter name

Example:

This example creates the ListName list parameter and adds it to the

newly created part:

Set CATDocs = CATIA.Documents

Set part1 = CATDocs.Add(“CATPart”)

Set list1 = part1.Part.Parameters.CreateList (“ListName”)

Parameters: i_name (str) –
Return type: ListParameter

create_real(i_name: str, i_value: float) → pycatia.knowledge_interfaces.real_param.RealParam¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Func CreateReal(CATBSTR iName,

double iValue) As RealParam

Creates a real parameter and adds it to the part’s collection of

parameters.

Parameters:

iName

The parameter name

iValue

The parameter value

Example:

This example creates the ReliabilityRate real parameter and adds it to

the newly created part:

Dim CATDocs As Documents

Set CATDocs = CATIA.Documents

Dim part1 As Document

Set part1 = CATDocs.Add(“CATPart”)

Dim rate As RealParam

Set rate = part1.Part.Parameters.CreateReal (“ReliabilityRate”, 2.5 )

Parameters

i_name (str) –
i_value (float) –

Return type

RealParam

create_set_of_parameters(i_father: pycatia.system_interfaces.any_object.AnyObject) → None¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Sub CreateSetOfParameters(AnyObject iFather)

Creates a set of parameters and appends it to argument iFather.

Parameters: i_father (AnyObject) –
Return type: None

create_string(i_name: str, i_value: str) → pycatia.knowledge_interfaces.str_param.StrParam¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Func CreateString(CATBSTR iName,

CATBSTR iValue) As StrParam

Creates a string parameter and adds it to the part’s collection of

parameters.

Parameters:

iName

The parameter name

iValue

The parameter value

Example:

This example creates the responsible string parameter and adds it to

the newly created part:

Set CATDocs = CATIA.Documents

Set part1 = CATDocs.Add(“CATPart”)

Set density = part1.Part.Parameters.CreateString (“responsible”, “The Boss”)

Parameters

i_name (str) –
i_value (str) –

Return type

StrParam

get_name_to_use_in_relation(i_object: pycatia.system_interfaces.any_object.AnyObject) → str¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Func GetNameToUseInRelation(AnyObject iObject) As CATBSTR

Returns a correct name of a feature to use it in a relation.

Parameters: i_object (AnyObject) –
Return type: str

has_parameters()¶

Returns: bool

is_list_parameter(index: pycatia.types.general.cat_variant)¶

Parameters: index (cat_variant) – parameter name or parameter number
Returns: bool
Return type: bool

is_parameter(index: pycatia.types.general.cat_variant)¶

Parameters: index (cat_variant) – parameter name or parameter number
Return type: bool

item(index: pycatia.types.general.cat_variant) → pycatia.types.general.any_parameter¶

Note

CAA V5 Visual Basic help: Item

o Func Item( CATVariant iIndex) As Parameter

Retrieves a parameter using its index or its name from the from the

Parameters collection.

Parameters:

iIndex

The index or the name of the parameter to retrieve from

the collection of parameters.

As a numeric, this index is the rank of the parameter

in the collection.

The index of the first parameter in the collection is 1, and

the index of the last parameter is Count.

As a string, it is the name you assigned to the parameter using

the

activateLinkAnchor(‘AnyObject’,’Name’,’AnyObject.Name’) property or when

creating the parameter.

Examples:

This example retrieves the last parameter in the parameters

collection:

Set lastParameter = parameters.Item(parameters.Count)

Parameters: index (cat_variant) –
Return type: any_parameter

remove(i_index: pycatia.types.general.cat_variant) → None¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Sub Remove(CATVariant iIndex)

Removes a parameter from the Parameters collection.

Parameters:

iIndex

The index or the name of the parameter to remove from the

collection of parameters. As a numerics, this index is the rank of the

parameter in the collection. The index of the first parameter in the collection

is 1, and the index of the last parameter is Count. As a string, it is the name

you assigned to the parameter using the

AnyObject.Name property or when creating the parameter.

Example:

This example removes the “depth” parameter from the parameters

collection.

parameters.Remove(“depth”)

Parameters: i_index (cat_variant) –
Return type: None

property root_parameter_set: ParameterSet¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445): o Property RootParameterSet() As ParameterSet (Read Only)

Returns the root parameter set of a document. If it doesn’t exist, it is

created.

Return type: ParameterSet

sub_list(i_object: pycatia.system_interfaces.any_object.AnyObject, i_recursively: bool) → pycatia.knowledge_interfaces.parameters.Parameters¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445)): o Func SubList(AnyObject iObject,

boolean iRecursively) As Parameters

Returns a sub-collection of parameters aggregated to an

object.

Parameters:

iObject

The object used to filter the whole parameter collection to get the

resulting sub-collection.

iRecursively

A flag to specify if children parameters are to be searched for in

the returned collection

Example:

This example shows how to retrieve a collection of parameters that

are associated to a Pad.

Dim Parameters1 As Parameters

Set Parameters1 = CATIA.ActiveDocument.Part.Parameters gets the collection of parameters

in the part

Dim Body0 As AnyObject

Set Body0 = CATIA.ActiveDocument.Part.Bodies.Item ( “MechanicalTool.1” )

Dim Pad1 As AnyObject

Set Pad1 = Body0.Shapes.Item ( “Pad.1” ) gets the pad Pad.1

Dim Parameters2 As Parameters

Set Parameters2 = Parameters1.SubList(Pad1,TRUE) gets the collection of parameters that

are under the pad Pad.1

Parameters

i_object (AnyObject) –
i_recursively (bool) –

Return type

Parameters

property units: pycatia.knowledge_interfaces.units.Units¶

Note

CAA V5 Visual Basic Help (2020-06-11 12:40:47.360445): o Property Units() As Units (Read Only)

Returns the collection of units.

Return type: Units

pycatia.knowledge_interfaces.parameters¶

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